Isosurface Output

Isosurface Output in Flow360 lets you visualize flow field variables on surfaces of constant value within the computational domain. This is particularly useful for identifying and analyzing coherent structures like vortices, shock waves, or temperature contours.

---

Available Options

Option	Description	Applicable
Output fields	Flow variables to include in the output	always
Output format	Format for saving isosurface data	always
Save interval	When to save outputs	always
Frequency	How often to save outputs	when Save interval is Custom
Frequency offset	Time step at which to start the output animation	when Save interval is Custom
Isosurfaces	Define one or more isosurfaces	always

See also

For the underlying physics and configuration of outputs, see the Output Configuration user guide.

---

Global Time Stepping in Child Cases

When working with child cases (cases forked from a parent simulation), it’s important to understand that the Frequency and Frequency offset parameters refer to the global time step, which is transferred from the parent case.

Example: If the parent case finished at time_step=174, the child case will start from time_step=175. If Frequency=100 is set in the child case, the output will be saved at global time steps 200 (25 time steps into the child simulation), 300 (125 time steps into the child simulation), etc. Frequency offset also refers to the global time step, meaning that if in the previously mentioned child case, Frequency offset=50 was set (with Frequency=100), the output would be saved at global time steps 250 (75 time steps into the child simulation), 350 (175 time steps into the child simulation), etc.

---

Detailed Descriptions

Output fields

Select the flow variables to include in the isosurface output.

• Default: None

• Example: Mach, pressure, velocity

Notes: isosurface outputs support all Universal Fields. See the Available Output Fields page for a complete reference, including commonly used fields for isosurface visualization.

Output format

The file format used to save the isosurface output data.

• Default: paraview

• Example: ["paraview", "tecplot"]

• Options: (multi-select; choose one or more)

  • paraview

  • tecplot

  • vtkhdf

  • ensight

Notes:

• Choose the format that best suits your post-processing workflow.

• The Output format control is multi-select: pick one or more of paraview, tecplot, vtkhdf, or ensight. See Output Formats for file extensions and details.

Save interval

Choose the points in the simulation where the results are saved.

• Default: Save at end

• Options:

  • Save at end

  • Custom (only available when Time stepping is Unsteady)

Notes:

• Choose Save at end to save only the final results of the simulation.

• Choose Custom to save the results in given intervals.

Frequency

How often to save outputs, in number of physical time steps.

• Default: -1 (only at the end of simulation)

• Example: 100 — saves output every 100 physical time steps.

  • Standalone case: If you start a simulation from time_step=0 with frequency=100, outputs are saved at time steps 100, 200, 300, etc.

  • Parent-child case: If the parent finished at time_step=174, the child starts from time_step=175. With frequency=100 in the child, outputs are saved at global time steps 200 (25 steps into child), 300 (125 steps into child), 400 (225 steps into child), etc.

Notes:

• Higher frequencies provide better temporal resolution but increase storage requirements.

• Important for child cases - this parameter refers to the global time step (see Global Time Stepping).

• This setting is only applicable for unsteady cases.

Frequency offset

The time step at which to start the output animation.

• Default: 0 (beginning of simulation)

• Example: 1000 — with frequency=100, outputs are saved at time steps 1000, 1100, 1200, etc.

  • Standalone case: If you start a simulation from time_step=0 with frequency=100 and frequency_offset=1000, outputs are saved at time steps 1000, 1100, 1200, etc.

  • Parent-child case: If the parent finished at time_step=174, the child starts from time_step=175. With frequency=100 and frequency_offset=200 in the child, outputs are saved at global time steps 200 (25 steps into child), 300 (125 steps into child), 400 (225 steps into child), etc.

Notes:

• Useful when you want to skip initial transient flow development.

• Important for child cases - this parameter refers to the global time step (see Global Time Stepping).

• This setting is only applicable for unsteady cases.

Assigned isosurfaces

Define one or more isosurfaces by specifying a field variable and iso-value.

• Default: None

• Definition parameters:

  • Name: A unique identifier for the isosurface

  • Field: The flow variable used to define the isosurface

  • Iso-value: The constant value of the field variable that defines the isosurface

• Example: qcriterion = 0.001

---

Available Isosurface Fields

Isosurfaces can be defined based on the following field variables:

• p - Pressure (non-dimensional)

• rho - Density (non-dimensional)

• Mach - Mach number (non-dimensional)

• qcriterion - Q criterion (for vortex identification) (non-dimensional)

• s - Entropy (non-dimensional)

• T - Temperature (non-dimensional)

• Cp - Coefficient of pressure (non-dimensional)

• Cpt - Total pressure coefficient (non-dimensional)

• mut - Turbulent viscosity (non-dimensional)

• nuHat - Spalart-Almaras variable (non-dimensional)

• vorticityMagnitude - Vorticity Magnitude (non-dimensional)

---

💡 Tips

Choosing a field and iso-value for a given flow feature

• To visualize vortices, create an isosurface of qcriterion at a small positive value. A good starting point is Mach² / WingSpan² for aircraft or TipMach² / RotorDiameter² for rotor flows (the auto-generated default is RefMach² / (all walls' bounding box length)²). Use smaller values to reveal more vortical structures, larger values to isolate only the strongest vortices.

• To visualize shock waves, create an isosurface of Mach around 1.0 (for transonic flows), or of a density/pressure gradient for a cleaner shock front.

• To visualize thermal features, create an isosurface of T (temperature); use several iso-values to show temperature stratification.

• To visualize separation and recirculation regions, create an isosurface of velocity (or skin friction) near zero.

---

❓ Frequently Asked Questions

• How do I choose the right iso-value for Q-criterion visualization?

  Start with a value based on the flow characteristics:

  • For aircraft: Try Mach² / WingSpan²

  • For rotors: Try TipMach² / RotorDiameter²

  • Decrease the value if you want to see more vortical structures

  • Increase the value if you want to focus only on strongest vortices

  • Experiment with different values, starting with orders of magnitude (0.1, 0.01, 0.001)

• Can I create multiple isosurfaces with different fields in a single output?

  Yes! You can define multiple isosurfaces in a single isosurface output:

  • Each with different fields (e.g., one for qcriterion, one for Mach)

  • Each with different iso-values

  • All sharing the same output fields and frequency settings This approach is more efficient than creating multiple separate isosurface outputs.

• Why are my isosurfaces flickering in animations?

  Isosurface flickering can occur due to:

  • Unsteady flows where structures evolve rapidly

  • Iso-values too close to background noise levels

  • Insufficient temporal resolution (increase output frequency)

  • Consider time-averaging for statistical visualization of unsteady features

• How large are isosurface output files typically?

  File sizes for isosurfaces are generally much smaller than volume outputs:

  • Size depends on the complexity of the isosurface (how many triangles are needed to represent it)

  • More complex flow features and lower iso-values typically generate larger files

  • Each output field adds data to every point on the isosurface

  • For a typical simulation, isosurface files might be 10-100 MB per timestep (compared to GB for volume outputs)

• Why is my isosurface broken or incomplete?

  Broken isosurfaces might occur because:

  • The iso-value is too high, breaking continuous structures

  • The feature doesn’t exist in parts of the domain

  • Flow features are evolving (especially in unsteady simulations)

  • Output frequency may be too low to capture continuous evolution

---

🐍 Python Example Usage

See also

Python API reference: IsosurfaceOutput, Isosurface.

# Example of configuring isosurface output using Flow360 Python API
import flow360 as fl
from flow360 import u

# Define multiple isosurfaces with different fields and values
isosurface_output = fl.IsosurfaceOutput(
    name="Flow Structures",
    output_format=["paraview"],
    isosurfaces=[
        fl.Isosurface(
            name="Vortex_Cores",
            iso_value=0.001,
            field="qcriterion",
        ),
        fl.Isosurface(
            name="Shock_Wave",
            iso_value=1.0,
            field="Mach",
        ),
        fl.Isosurface(
            name="Hot_Region",
            iso_value=1.2,
            field="T",
        ),
    ],
    output_fields=["velocity", "pressure", "Mach"],
    frequency=100,  # Save every 100 time steps
    frequency_offset=0,  # Start at the beginning of simulation
)

# Add isosurface output to simulation parameters
simulation_params = fl.SimulationParams(
    # ... other simulation parameters ...
    outputs=[isosurface_output]
)